PowerMILL 指令收集帖

moki · 发表于 2008-12-11 14:57:00

马上注册，结识高手，享用更多资源，轻松玩转三维网社区。

您需要登录才可以下载或查看，没有帐号？注册

x

PowerMILL 指令收集帖

大家都知道，可以通过看PowerMILL的命令窗口，知道大部分的命令

但是有些是看不到的，特意开贴收集，加分奖励！

本着我为人人，人人为我，的互助精神，请大家踊跃参与!

moki · 发表于 2008-12-11 14:57:37

Multiple Toolpaths and Sessions
Commit Toolpath
Once a roughing or finishing path has been computed it can be committed to a list of toolpaths. Similary a boundary can be committed to this list (in this case a toolpath is produced but the original boundary is kept intact. (See also edit boundary commit)
  ||--COMMIT--|--FCUTTERPATHS--|       ||
            |             |--name--||
            |--RCUTTERPATHS--|       ||
            |             |---;----||
            |----BOUNDARY----|       ||
The committed toolpath can either be given a name or if the ";" character is used then a unique numeric name is automatically assigned to the toolpath.
A valid name can contain any number of letters, digits or underscores (_) and can optionally be surrounded by either single or double quotes.
Rename Toolpath
This command is used to change the name of the selected toolpath.
  ||--RENAME--|--TOOLPATH--|--name--||
The new name can be any valid name but a toolpath of the same name cannot already exist.
Select Toolpath
Once a toolpath has been commited it can be selected. The selected toolpath can be used in operations such as cutfile creation, ViewMILL and toolpath editing
  ||--SELECT--|--TOOLPATH--|--name--||
                        |       ||
                        |--pick--||
A toolpath is selected by either typing it's "name" or by picking it with the cursor. If more than one toolpath is picked then a list of picked paths is printed and the pick can either be refined by further picking / unpicking or a name can be entered.
When a toolpath is selected all of the flags and parameters that were used to create that toolpath are loaded back to become the current values used to create new paths.
Automatic Form Raising
By default, when a toolpath is selected, the machining strategy form associated with the toolpath is raised. The behaviour can be controlled by using the following command.
  ||--EDIT--|--PREFERENCE--|--SELRAISEFORM--|--YES--||
                                          |    ||
                                          |--NO---||
Automatic Selected Toolpath Drawing
By default, when a toolpath is selected it is drawn, even if it is undrawn before the selection. This behaviour can be switched off by using the following command:
  ||--EDIT--|--PREFERENCE--|--AUTODRAW--|--YES--||
                                    |    ||
                                    |--NO---||
Automatic Parameter Loading
By default, when a toolpath is selected, the machining parameters associated with the toolpath are loaded into the PowerMILL forms. The behaviour can be controlled by using the following command.
  ||--EDIT--|--PREFERENCE--|--AUTOLOAD--|--YES--||
                                    |    ||
                                    |--NO---||
The following command is provided to manually load the parameters from the currently selected toolpath.
  ||--LOAD--|--TOOLPATH--|--PARAMETERS--||
Delete Toolpath
Commited toolpaths can be deleted using the DELETE TOOLPATH command:
  ||--DELETE--|--TOOLPATH--|--name--||
                        |       ||
                        |---;----||
                        |       ||
                        |--ALL---||
Specifying the ";" character deletes the selected toolpath. If ALL is used then all toolpaths are deleted (after a warning).
--------------------------------------------------------------------------------
Session Files
A session file is used to store toolpath data in a form which can easily be reloaded at a later date. By convention a session file has the suffix .psf (Powermill Session File).
Keep Session
All of the toolpaths that have been commited are saved to a disc file.
  ||--KEEP--|--SESSION--|--file_name--||
Get Session
The session file is reloaded by using the command GET SESSION.
  ||--GET--|--SESSION--|--LOAD---|--file_name--||
                     |       |
                     |--MERGE--|
LOAD
All of the data from session file is loaded and existing toolpaths are deleted.
MERGE
All of the data is loaded but any existing toolpaths are not deleted. If the session file contains a toolpath with the same name as an existing toolpath then the new toolpath is renamed. The new toolpath with have _n appended to it's name where n is a number which makes the name unique.
--------------------------------------------------------------------------------
Get Toolpath
Import toolpaths from cutfiles or DUCT Picture into the committed toolpath list by the command:
  ||--FILE--|---GET---|--TOOLPATH-----|--file_name--||
                  |             |
                  |--TOOLPATHCUT--|
                  |             |
                  |--TOOLPATHPIC--|
Ordering of Toolpaths
The toolpaths are generally stored in the order that they are created. This order can be seen when using the commited toolpath form, or on Windows via the PowerMILL tree browser. It is possible to reorder the toolpaths so that they are displayed in a different sequence in these two graphical controls. On Windows the order can be altered by dragging the toolpaths within the tree, however commands are also available to alter this ordering.
  ||--ORDERSESSION--|---TOOLPATH---|--name1--|--AFTER--|--name2--||
                                          |                ||
                                          |--FIRST--|---------||
The first form of the command makes toolpath name1 appear after toolpath name2 in the graphical controls. The second form of the command makes toolpath name1 appear as the first toolpath in the graphical controls.
Entity Attributes
Entities which are stored in the session file can be given certain global attributes
Naming Templates
  ||--EDIT--|--ENTATTRIBUTE--|--TEMPLATE--|-->>

  |--ALL-------|--OFF-------||
  |                      ||
  |--ent_type--|--template--||
  |          |          ||
  |          |--OFF-------||
  |                      ||
  |--PRINT-----|------------||
Templates are used when PowerMILL creates a new entity and assigns it a unique name. By default PowerMILL creates a name which is simply a number, however each entity can be assigned a template which is used to create the name. The simplest form of the template command is as shown below:
EDIT ENTATTRIBUTE TEMPLATE GROUP 'finishing'
Any new group entities which are created have their names prefixed with finishing so they might be called finishing1, finishing2 etc. PowerMILL is still using a number to make the name unique, which is being appended to a users naming template.
If the template contains a percent character (%) then this is used to indicate where PowerMILL should insert the number, to make the name unique. As an example:
EDIT ENTATTRIBUTE TEMPLATE TOOLPATH 'semi%finish'
Would cause names such as semi1finish, semi2finish etc. If a template contains more than one percent character then only the first is used to determine where to insert the number. Extra percents simply become part of the entity name.
Templates can be disabled for all entities by using the command:
EDIT ENTATTRIBUTE TEMPLATE ALL OFF
or for an individual entity by including the entity type in the command, as an example to switch of templates for Patterns, the following command would be used:
EDIT ENTATTRIBUTE TEMPLATE PATTERN OFF
Normally the current template for a particular entity type can be seen by right clicking over the entity node in the tree browser. However the command:
EDIT ENTATTRIBUTE TEMPLATE PRINT
can be used if required. Example output is shown below:
3 Templates
pmlEntGroup None
pmlEntPattern core
pmlEntToolpath roughing
Entity types are all prefixed by pmlEnt which signifies PowerMILL Entities, entities which have never had a template in the current session are not shown. ie. Workplanes are not shown in the above listing as no template had been set for them. Groups have the word 'None' next to them which indicates that the template has been switched off for groups. (The print command really only exists for debugging the program)
Listing Entities
The PRINT ENTITY command will print the names of all entities of a given type and indicate which, if any, is the active entity.
  ||--PRINT--|--ENTITY--|--ent_type--||
So the command PRINT ENTITY TOOLPATH would display something like:
3 Toolpath
  'Rough1'
* 'Semi'
  'Finish'
The first line of the print out shows the number of entities, of a given type. The * in the first column of the printout shows which entity is active. The command is useful for OLE programs and also for UNIX users who don't have the advantage of using the PowerMILL Explorer.
Toolpath Attributes
The following command can be used to control the drawing of certain toolpath attributes:
  ||--EDIT--|--TPATTRIBUTE--|--ALL---|-->>
                        |       |
                        |--name--|
                        |       |
                        |---;----|
  |--LINKS---|--ON------|---------||
  |       |       |
  |       |--OFF-----|
  |
  |--POINTS--|--ON------|---------||
         |       |
         |--OFF-----|
         |
         |--COLOUR--|--index--||
By default, toolpaths are drawn to the screen along with any linking moves. The following example command will switch off the drawing of toolpath links for all existing toolpaths:
EDIT TPATTRIBUTE ALL LINKS OFF
A toolpath's links drawing flag is maintained across sessions. See KEEP SESSION.
NOTE - This command deprecates the SET|UNSET TOOLPATHLINKS command.
Sometimes, usually for the purposes of analysis, it is desirable to view the individual points on a toolpath. The following example command will switch on the drawing of toolpath points for the toolpath named finishing:
EDIT TPATTRIBUTE 'finishing' POINTS ON
A toolpath's points drawing flag is maintained across sessions. See KEEP SESSION.
NOTE - This command deprecates the SET|UNSET TOOLPATHPOINTS command.
It also possible to control the drawing colour of toolpath points. The following example command will set the colour of toolpath points for the selected toolpath to colour index 5:
EDIT TPATTRIBUTE ; POINTS COLOUR 5
A toolpath's points colour is not maintained across sessions.

[ 本帖最后由 moki 于 2008-12-16 18:41 编辑 ]

moki · 发表于 2008-12-11 14:57:42

Z Height List Model
The list of Z heights represents the heights at which the Triangles Model will be sliced. The commands available are:-
Edit
Modify the Z heights in the list by either:-
An absolute value in Z.
A number of Z heights divided evenly down the block.
A stepdown distance.
An intermediate number of Z heights between existing Z heights in the list.
The command to change the generation mode is:-
  ||--EDIT--|--ZHEIGHT--|--MODE--|--VALUE---------||
                              |             ||
                              |--NUMBER--------||
                              |             ||
                              |--STEPDOWN------||
                              |             ||
                              |--INTERMEDIATE--||
The command to change the value applied to the generation mode is:-
  ||--EDIT--|--ZHEIGHT--|--MODEVALUE--|--value--||
The command to finally generate the z heights is:-
  ||--PROCESS--|--ZHEIGHTS--||
Note that no existing Z height will be deleted from the list as a result of this edit command. Note also that the flag CSTEPDOWN, when SET, forces the distance between step downs to be constant thus avoiding the lowest Z height taking a cut smaller than the rest.
The Z height list can also be edited by appending and deleting Z heights held by a named toolpath, pattern, or featureset entity:-
  ||--EDIT--|--ZHEIGHT--|--entity-type--|--name--|--APPEND--|--|--BOTTOM--||
                                             |       |  |       ||
                                             |--DELETE--|  |--TOP-----||
                                                            |       ||
                                                            |--ALL-----||
Draw
Draw the Z heights on the block. Note that these are drawn relevant to the active Workplane. If the Workplane is deactivated then they are is automatically re drawn relevant to the World co-ordinates.
  ||--DRAW--|--ZHEIGHTS--||
Undraw
  ||--UNDRAW--|--ZHEIGHTS--||
Delete
Delete all Z heights, pick as many as required or delete at a known value. Note that deleting a Z height has the implication of deleting any Slice and Cutter Paths at the same height.
  ||--DELETE--|--ZHEIGHTS--|--ALL-------||
                        |          ||
                        |--pick------||
                        |          ||
                        |--z height--||
Size
Print the height of one or more picked Z heights.
  ||--SIZE--|--ZHEIGHTS--|--pick--||

--------------------------------------------------------------------------------
Slices Model
The Slices Model contains the Slices created as a result of slicing the Triangles Model bounded by the Block Model at the Z Heights in the Z Heights List with the Tool Model. Note that the slices are stored in Absolute World co-ordinates and are therefore not affected by any changes in the Workplane.
Draw
  ||--DRAW--|--SLICES--||
Undraw
  ||--UNDRAW--|--SLICES--||
Draw Pixels
Only available if the Slices are drawn.
  ||--DRAWPIX--|--SLICES--||
Undraw Pixels
Only available if the Slices are drawn.
  ||--UNDRAWPIX--|--SLICES--||
Animate Redraw slices one span at a time with a time delay between each drawn span. Only available if the slices are drawn:-
  ||--ANIMATE--|--SLICES--|--time delay--||
Get
Read slices from a DUCT Picture file
  ||--GET--|--SLICES--|--filename--||
Note that this command will delete the existing triangle model, roughing toolpaths, slices and Z heights. It will then automatically create a block around the slice limits
Load
Load slices from a committed roughing toolpath
  ||--EDIT--|--AREACLEAR--|--SLICES--|--LOAD--||
Users need to be aware that its currently possible to load a set of slices that may not have been created with the current model. Subsequently, this is currently a PREVIEW function and should be used with care.
Delete
You can delete the slice model via either levels, pockets or areas. When deleting levels you can pick as many as required or specify only one. When deleting pockets you pick the top contour of the pocket you require and PowerMILL will determine which contours below it constitute a pocket. When deleting areas you pick any contour within an area and PowerMILL determines which other contours belong to the area.
Note that deleting areas may destroy the pocket information held with the slice model. This means that pocket deletion and machinining may be unavailable
It is possible to undo the level, pocket and area deletion. This means that each can be deleted (or effectivly masked) and then restored with the undo command. Note that the undo commands have the effect of restoring ALL slice data that has been deleted via either the pocket or area deletion commands.
  ||--DELETE--|--SLICES--|--ALL-------------------------------||
                     |                                  ||
                     |--BYVALUE--|--z height--------------||
                     |                                  ||
                     |--BYPICK--|--POCKETS--|--pick item--||
                                 |          |          ||
                                 |--LEVELS---|          ||
                                 |          |          ||
                                 |--AREAS----|          ||
                                 |                      ||
                                 |--UNDO-------------------||
Note that deleting slices or pockets has the implication of deleting any Cutter Paths associated with them. Note also that the undo command only restores the pocket and not the Cutter Paths.
See also Area Filtering.
Flags & Parameters
The following flags and parameters are taken into consideration during slice generation:-
RTHICKNESS
Specifies how much material is to be left on the Triangle Model after slicing.
RTOLERANCE
Specifies the +/- accuracy of the thickness allowance i.e. with a thickness of 1 and a tolerance of 0.1 the possible thickness would be in the range 0.9 to 1.1. It is therefore important to ensure that the tolerance does not exceed the thickness as this may result in machining into the model.
RFEMALE
A flag that specifies whether to machine a male or female part. A male part represents the actual Triangle Model. A female part represents the mould required to manufacture the Triangle Model. Note that in order to create a female part you may need to rotate the Triangle Model by 180?in the Z axis using the ROTATE TRIANGLE command or by rotating the active Workplane.
The commands available on these parameters are:-
Edit
Edit the thickness and tolerance.
  ||--EDIT--|--RTHICKNESS--|--thickness--||
         |                         ||
         |--RTOLERANCE--|--tolerance--||
Set and Unset
Set and Unset the RFEMALE flag.
  ||--SET--|--RFEMALE--||
  ||--UNSET--|--RFEMALE--||

--------------------------------------------------------------------------------
Holes List Model
This is a list of drilling hole positions initially created as a result of producing Drilling Paths. These holes can be moved to any suitable position in the Slices Model to produce a more effective drilling operation.
The commands available on the Holes List are:-
Edit
ADD and MOVE are available to edit the holes.
Add a new hole by digitising a point INSIDE the Slices Model or by entering an absolute XYZ value.
Move a hole by picking an existing hole and digitising a new point. You can also select a hole by typing its absolute location and enter the new position by typing a new absolute location.
  ||-EDIT-|-HOLES-|-ADD--|-DIGITISE----------------||
               |    |                      ||
               |    |-x-|-y-|-z---------------||
               |                               ||
               |-MOVE-|-PICK--|-DIGITISE--------||
                     |                      ||
                     |-x-|-y-|-z-|-|-x-|-y-|-z-||
Note that once picking has started, you will need to press the right hand mouse button to leave picking mode.
Delete
Delete a hole by either picking or by typing an absolute value.
  ||--DELETE--|--HOLES--|---pick----||
                     |          ||
                     |-x-|-y-|-z-||
Note that once holes have been picked, you will need to press the right hand mouse button to delete the picked holes.
Size
Print the location, depth and radius of a picked hole.
  ||--SIZE--|--HOLES--|--pick--|
Draw
  ||--DRAW--|--HOLES--||
Undraw
  ||--UNDRAW--|--HOLES--||

--------------------------------------------------------------------------------
Drill and Cutter Paths
These two types of paths are both sequential collections of Cutter Moves generated as a result of applying the Roughing Strategy Options to the Slices Model.
Drill Paths are the cutter moves that produce the pre-drilled holes in the Block which are necessary when a non-plunging cutter is to be used for Level Moves (that is when RMOVES is set to DRILL). The position of these drilling holes can be modified by the Holes List.
Cutter Paths are the moves that do the roughing.
The command to produce both the Drill and Cutter Paths is:-
  ||--ROUGH--|--TRIANGLES--||
The commands available are:-
Keep
Keep toolpaths to either a DUCT picture file or a Cutter Location file:-
  ||--KEEP--|--DRILLPATHS----|--file name--||
         |                            ||
         |--RCUTTERPATHS--|--file name--||
Draw

  ||--DRAW--|--DRILLPATHS----||
         |             ||
         |--RCUTTERPATHS--||
Note that a flag called RCUTTERPATHSLINK is provided to control whether the linking moves are shown. When SET (the default state) link moves are shown and when UNSET, they are removed.
Animate

  ||--ANIMATE--|--DRILLPATHS----||
            |             ||
            |--RCUTTERPATHS--||
To fully understand the various roughing strategies we need to describe the various components of a Cutter Move. This consists of four types of tool movement relating to the location of the tool and its cutting status:-
Rapid Moves - used to move the tool in air at rapid speed.
Level Moves - used to get the tool from one pre-machined Level Area down to an unmachined Level Area.
Profile Moves - used to machine the Profiles associated with each Area.
Area Clearance Moves - used to machine the Area enclosed by the Profiles
Note that no metal removal is allowed during Rapid Moves.
Rapid Cutter Moves
Rapid moves are performed at rapid speed (defined by the parameter RSPEED) and are required to move the tool between two points in the shortest possible time. They generally consist of these three moves:-
UP - An up move from the last cutting position to a safe Z height.
ACROSS - An across move at constant Z to the new start cutting position.
DOWN- A down move to the new start Z height.
There are also four parameters associated with Z heights that are used during rapid moves:-
SAFZ - Absolute value in Z which the tool will lift up to and move across at.
STAZ - Absolute value in Z which the tool will move down to.
ISAFZ - Incremental value in Z above a pre-machined level to which the tool will lift up to and move across at.
ISTAZ - Incremental value in Z above a pre-machine level to which the tool will move down to.
These are described in more detail in the section on Tool Z Heights.
Level Cutter Moves
Level moves (defined by the parameter LMOVES) are required to move the tool between start Z and the level to be machined. The operation is performed at plunge rate (defined by parameter PRATE) and can be one of the following:-
PLUNGE - Plunges at Plunge Rate directly into the model with no consideration for pre-drilled holes.
RAMP - Ramps in at anangle defined by the parameters defined below.
DRILL - Plunges at Plunge Rate into pre-drilled holes created by the Drill Paths. These will automatically produce a Hole List which can be modified later.
The command to edit the LMOVES parameter is:-
  ||--EDIT--|--LMOVES--|--PLUNGE--||
                     |       ||
                     |--RAMP----||
                     |       ||
                     |--DRILL---||
The commands to specifically control the ramping are:-
  ||--EDIT--|--RAMP--|--ZIGANGLE--|--angle--||
                  |                   ||
                  |--FOLLOW--|--PROFILE--||
                  |       |          ||
                  |       |--LINE-----||
                  |       |          ||
                  |       |--CIRCLE---||
                  |                   ||
                  |--DIAMETER-|-diameter-||
                  |                   ||
                  |--FINITELENGTH--|--Y--||
                  |             |    ||
                  |             |--N--||
                  |                   ||
                  |--LENGTH---|--length--||
                  |                   ||
                  |--INDYZAG-------|--Y--||
                  |             |    ||
                  |             |--N--||
                  |                   ||
                  |--ZAGANGLE--|--angle--||
Where:-
ZIGANGLE - controls the zig angle within the range of 0.01 to 89 degrees.
FOLLOW - controls the direction of the ramp i.e. either along the touching profile or along a line running normal to the contact point or around a circle. Note that the line method is automatically used if a circle cannot be accommodated into the area and the profile method is automatically used if a line cannot be accommodated in the area.
DIAMETER - controls the circle diameter. Note that this value is represented in Tool Diameter Units.
FINITELENGTH - controls whether the ramp length if finite or infinite.
LENGTH - controls the ramp length. Only valid if FINITELENGTH is set to Y. Note that this value is represented in Tool Diameter Units.
INDYZAG - controls whether the zig angle is independant of the zag angle. Only valid if FINITELENGTH is set to Y.
ZAGANGLE - controlsthe zag angle within the range of 0 to 89 degrees. Only valid if INDYZAG is set to Y.
When SET, a flag called OUTSIDE forces the Level moves to approach the Block Model from the outside. Approachable Spans in the Slice Model are drawn in magenta to indicate their availability for this type of level move. Note that this option is not available if the Block Model is defined by the 2D Picture or 3D Triangle Model.
Profile Cutter Moves
These are optional profile moves (defined by the parameter PMOVES) to guide the tool around the profile at feed rate (defined by the parameter FRATE) and can be performed either before, during or after the Area Cutter Moves.
The during option is a special form of profile move that deserves further explanation. Using the before or after options forces the tool to perform two Cutter Move operation with associated Rapid and Level moves. Using the during means that a profile move is performed the first instance an area clearance path touches that profile.
The command to edit PMOVES is:
  ||--EDIT--|--PMOVES--|--NONE----||
                     |       ||
                     |--BEFORE--||
                     |       ||
                     |--DURING--||
                     |       ||
                     |--AFTER---||
You can force Profiling Cutter Paths to use particular milling technologies via the parameter PCUTDIR:-
  ||--EDIT--|--PCUTDIR--|--ANY-----------||
                     |             ||
                     |--CLIMB---------||
                     |             ||
                     |--CONVENTIONAL--||
It is sometimes possible to omit the Outside Profile moves as they can be cleared out by the area clearance moves. A flag called POUTSIDE, when SET, forces the outer profiles to be machined and when UNSET forces them to be ignored. When using blocks that do not completely enclose the Triangles Model, the moves will only take place where the spans lie within the block. Note that all spans to be ignored are drawn in a dashed line style. Note also that this option is not available if the Block Model is defined by the 2D Polyline or 3D Triangles Model.
Area Clearance Cutter Moves
The area clearance moves are responsible for clearing the material contained within the profiles. The current strategies supported are Profile, Raster and Offset. These are described in more detail in the next section.
Area clearance strategies are selected via the edit command on the RSTRAT parameter:-
  ||--EDIT--|--RSTRAT--|--PROFILE--||
                     |          ||
                     |--RASTER---||
                     |          ||
                     |--OFFSET---||
The stepover between Cutter Path passes is defined by the parameter OVER:-
  ||--EDIT--|--OVER--|--stepover--||
You can force Area Clearance Cutter Paths to use particular milling technologies via the parameter ACUTDIR:-
  ||--EDIT--|--ACUTDIR--|--ANY-----------||
                     |             ||
                     |--CLIMB---------||
                     |             ||
                     |--CONVENTIONAL--||

--------------------------------------------------------------------------------
Raster Area Clearance Strategy
A raster area clearance strategy clears an area with equally spaced parallel lines laid across the profiles and joined together by cutting moves around the profiles.
You can force the raster stepover to be constant over the whole Area by setting a flag called CSTEPOVER. This ensures that raster Cutter Paths are guaranteed to lie on both edges of each Area so that an even cut will be maintained.
Two options are available when creating the raster paths:-
Angle - raster angle relative to the X axis.
Join Up Search Range - search range when joining rasters.
Raster Angle
The angle of the rasters can be defined manually (i.e. 33 degrees) or automatically. Auto calculation allows PowerMILL to select what it considers the best angle. The best angle can be based on an individual area, a whole level, each pocket or the whole model.
The Manual/Automatic action is controlled by the Flag AUTOANGLE. When AUTOANGLE is SET the Parameter AUTOANGLEMODE determines the search range:-
  ||--EDIT--|--AUTOANGLEMODE--|--AREA----||
                           |       ||
                           |--LEVEL---||
                           |       ||
                           |--POCKET--||
                           |       ||
                           |--MODEL---||
When AUTOANGLE is UNSET the Parameter RANGLE defines the raster angle to be used throughout the whole model:-
  ||--EDIT--|--RANGLE--|--angle---||
                     |       ||
                     |--XAXIS---||
                     |       ||
                     |--YAXIS---||
XAXIS and YAXIS are only provided to force the raster angle to 0 and 90 degrees respectively.
Join Up Search Range
A parameter called RJOIN controls the search range for join up moves between Raster Spans. A large value will ensure that the tool lifts the minimum number of times but it may also mean that the tool is spending large periods of time travelling around join up moves. Conversely, a small join up range will result in more lifts but less time travelling around join up moves.
The command to modify RJOIN is:-
  ||--EDIT--|--RJOIN--|--range--||
A flag called IRJOIN when SET forces an infinite join range and consequently invalidates any value in RJOIN.
Raster Span Optimisation
The definition of an unnecessary Raster Span is one that, if a tool were to pass along its length, would not remove any material. This can only happen if a profiling move has, or is about to, pass along the same area.
The two instances where unnecessary Raster Spans are found are:-
The first and possibly the last Raster Span of an area.
Where Raster Spans are shorter than the diameter of the Tool.
When SET, a flag called RSPANS forces unnecessary Raster Spans to be left unmachined. When UNSET, all raster spans are machined.
Minimise Full Width Cuts
Because of the searching nature of the raster pattern, it is possible for the tool to occasionally be cutting on its full width. This is not generally a problem when cutting soft material but can cause damage to the tool when cutting hard material. When SET, a flag called MINFULLWIDTH, removes all raster moves that could cause the tool to cut on its full width. Note that when SET, this flag disables the Join Up Search Range option.
--------------------------------------------------------------------------------
Offset Area Clearance Strategy
An offset area clearance strategy clears an area with contours generated by offsetting the initial slice. Subsequent offsets are taken of the previously offset slice until no further offset is possible.
The direction of offset moves can be controlled by the OFFSETDIRECTION variable:-
  ||--EDIT--|--OFFSETDIRECTION--|--INSIDEOUT--||
                              |          ||
                              |--OUTSIDE----||
                              |          ||
                              |--AUTO-------||
where:-
InsideOut - Machine from the innermost profile, moving outward
OutsideIn - Machine from the outmost profile, moving inward
Auto - Automatically select either of the previous methods based on whether a core or cavity is being machinined. The definition of a core is an area whose outermost boundaries are ALL lying on the outside of the block.
Detecting Unmachined Areas
Selecting a stepover distance greater than the tool radius can lead to small islands of material being left unmachined. Such stepover distances modify the offset behaviour of PowerMILL and result in small areas being automatically detected and machined by the inclusion of additional toolpaths that are integated into the main toolpath.
Machining Smallest Areas First
It is sometime advisable to machine the smallest offsets first to avoid the tool damage that can occur if these small offsets are machined last.
The order of machining can be controlled by the SMALLESTOFFSETSFIRST variable:-
  ||--EDIT--|--SMALLESTOFFSETSFIRST--|--ON---||
                                 |    ||
                                 |--OFF--||
The defualt value of this variable is OFF
--------------------------------------------------------------------------------
Pocket Machining
When SET, a flag called POCKET forces Areas to be machined in a pocket by pocket strategy. When UNSET Areas are machined Level by Level.
--------------------------------------------------------------------------------
Area Filtering
Area filtering enable areas to be automativally ignored based on their size relative to the tool diameter. This enabled small areas to be machined using a different method to large areas.
A parameter called AREAFILTERVALUE controls the threshold size that all areas are compared against. This value represents the ratio between the tool diameter and the longest principle axis of each individual area. For example, a value of 2.0 indicates that the length of the longest principle axis of an area is compared against twice the tool diameter of the tool used to generate the slice.
The command to modify AREAFILTERVALUE is:-
  ||--EDIT--|--AREAFILTERVALUE--|--value--||
The filtering action to peform on areas is controlled by the AREAFILTERMODE parameter. This enable you to remove either smaller or larger areas.
The command to modify AREAFILTERMODE is:-
  ||--EDIT--|--AREAFILTERMODE--|--NONE-----||
                           |          ||
                           |--LARGER---||
                           |          ||
                           |--SMALLER--||
Note that filtering takes place after the toolpaths have been calculated. This enables different filtering thresholds to be quickly used to determine the most appropriate value. Note also that drilling toolpaths are not affected by the filter so a single drilling toolpath can be used for any filtered toolpath. This does however mean that it is possible to generate a drilling move for an area that hasn't been machinined or a drilling move to a depth greater than required.
Note that it is also possible to achieve the same result as filtering by using the delete option.
Rest Roughing
Rest roughing is the process of generating roughing toolpaths that only remove material unmachined by a previous roughing toolpath.
The command to enable/disable rest roughing is:-
  ||--EDIT--|--AREACLEAR--|--REFERENCE--|--ENABLED--|--ON---||
                                                |    ||
                                                |--OFF--||
Once enabled, it is possible to select a reference roughing toolpath via the command:-
  ||--EDIT--|--AREACLEAR--|--REFERENCE--|--NAME--|--name--||
Any subsequent roughing toolpath will now only machine areas unmachined by the reference toolpath.

[ 本帖最后由 moki 于 2008-12-16 18:42 编辑 ]

JimGreen · 发表于 2008-12-11 16:13:04

顶啊,支持斑竹

hh749 · 发表于 2008-12-11 19:57:33

这个可能需要对宏比较有研究的知道的多一点

16805052 · 发表于 2008-12-12 08:13:51

期待ing。。。

2084592 · 发表于 2008-12-17 14:10:21

Toolpath EditingVarious options are available in PowerMILL for editing toolpaths. These are split into three types: transforms (mirror, move, rotate), altering the leads/links and limiting/verification. All of these have an option of keeping the original toolpath so that any mistake can be rectified. Transform ToolpathThe type of transform may be selected as follows: ||--EDIT--|--TOOLPATH--|--TRANSFORM--|--TYPE--|--MIRROR--|| | || |--MOVE----|| | || |--ROTATE--||The command to perform the toolpath transformation is:- ||--PROCESS--|--TPXFORM--||MirrorA mirror transformation requires a mirror line to be defined in the X-Y plane. This is done by a point and an angle (defined as anti-clockwise about the positive z-axis, with the x-axis at 0 degrees). The commands are as follows: ||--EDIT--|--TOOLPATH--|--TRANSFORM--|--POINTX--|--value--|| | | |--POINTY--| | | |--ANGLE---|MoveA move transformation (translation) requires any combination of x, y and z coordinates for the toolpath to move by. These are entered as follows: ||--EDIT--|--TOOLPATH--|--TRANSFORM--|--POINTX--|--value--|| | | |--POINTY--| | | |--POINTZ--|RotateA rotation transformation requires a point in the X-Y plane to rotate around and an angle (defined as anti-clockwise about the positive z-axis) to rotate by. The commands are as follows: ||--EDIT--|--TOOLPATH--|--TRANSFORM--|--POINTX--|--value--|| | | |--POINTY--| | | |--ANGLE---|Limit/Verify ToolpathThe limiting options allow the toolpath to by divided into two separate toolpaths. Either or both of these may be kept and edited further. Any open ends on the toolpath are joined using the active link method (see below) - this defaults to a retract to safe Z. Limit to PlaneTo select the limit to a plane option, the command is: ||--EDIT--|--TOOLPATH--|--LIMIT--|--PLANE--||The type of plane may be selected as follows: ||--EDIT--|--TOOLPATH--|--LIMIT--|--PLANEOPTIONS--|---SELECT----|| | || |------X------|| | || |------Y------|| | || |------Z------|| | || |---PICKING---|| | || |--SPECIFIED--||The select option places the limiting plane in the X, Y or Z plane in the middle of the block. The X, Y and Z options take an input of the appropriate coordinate. This may either be typed of picked with the cursor. The PICKING option requires two points to be picked with the cursor, the plane being formed by the line through these points and the normal to the screen view. The SPECIFIED option takes a typed input corresponding to a point on the plane and the normal to it. Limit to BoundaryTo select the limit to a boundary option, the command is: ||--EDIT--|--TOOLPATH--|--LIMIT--|--BOUNDARY--||The boundary forms a closed shape in either the X-Y plane or the view plane. The polygon is extruded along the direction perpendicular to a plane fitted through the first three points to give the shape used to limit the toolpath. Limit to PolygonTo select the limit to a polygon option, the command is: ||--EDIT--|--TOOLPATH--|--LIMIT--|--POLYGON--||The polygon is defined by a series of cursor clicks in the active view. This forms a closed shape which is then extruded along the view direction to give the shape used to limit the toolpath. Collision CheckerThe collision checker in PowerMILL warns of any tool holder and shank collisions that may occur while machining the current roughing, finishing or selected toolpath. On identifying these regions, PowerMILL prints the depth of the collision, highlights the toolpath, and recommends a new tool length to prevent the tool holder from colliding. Selected toolpaths are split if collisions are found and the tool lengths for the resulting toolpaths are set accordingly - i.e. the colliding toolpath will have a tool length which avoids collisions and the non-colliding toolpath will have the tool length that it was collision checked with. These two toolpaths will overlap by the required distance if an overlap has been set. If no collisions are found in the main segments of the toolpath the leads and links are checked. If lead or link collisions are found in the case of checking a roughing or finishing toolpath a warning is given. In the case of checking the selected toolpath a new toolpath is produced which has colliding links replaced with safe z links and colliding leads removed. The command to activate the collision checker is:- ||--PROCESS--|--COLLISION--||Edit The tool holder is defined by an upper diameter (UPDIA), a lower diameter (LOWDIA), and height (HEIGHT). The command syntax is:- ||--EDIT--|--COLLISION--|--UPDIA---|--value--|| | | |--LOWDIA--| | | |--HEIGHT--|The lower diameter must be less than or equal to the upper diameter. The tool shank is defined by a length(SHANKLEN) and diameter(SHANKDIA). The command syntax is:- ||--EDIT--|--COLLISION--|--SHANKLEN---|--value--|| | | |--SHANKDIA---|Set the collision checker to check either ROUGHING, FINISHING or SELECTED toolpaths with the command:- ||--EDIT--|-COLLISION-|-TOOLPATHS-|--ROUGHING---|| | || |--FINISHING--|| | || |--SELECTED---||Set the collision checker to check either TOOL HOLDER or SHANK or BOTH with the command:- ||--EDIT--|-COLLISION-|-CHECK-|--TOOLHOLDER---|| | || |--SHANK--------|| | || |--BOTH---------||The CLEARANCE represents a specified "safe" area around the tool holder/shank which is taken into account when checking for collisions. This is set by the command:- ||--EDIT--|-COLLISION-|--CLEARANCE--|--value--||The OVERLAP represents the distance that the colliding toolpath can be extended and so overlaps the non-colliding toolpath. This is set by the command:- ||--EDIT--|-COLLISION-|--OVERLAP--|--value--||Draw To draw the collisions the command is:- ||--DRAW--|--COLLISION--||To draw the tool holder and shank, the command is:- ||--DRAW--|--COLLISIONHOLDER--||Delete ||--DELETE--|--COLLISION--||Leads and LinksThe command to change the toolpath leads and links is:- ||--PROCESS--|--TPLEADS--||

scxdh · 发表于 2009-7-1 23:08:22

期待ing。。。

ZXY520 · 发表于 2009-8-8 17:17:28

能说下这些命令的用法和具体作用么

yue2233 · 发表于 2009-8-8 22:26:12

如何获取激活刀具的信息

hh749 · 发表于 2009-8-9 17:53:50

原帖由 yue2233 于 2009-8-8 22:26 发表 http://www.3dportal.cn/discuz/images/common/back.gif0 |+ R ~. A" O' g' @
如何获取激活刀具的信息

同样的问题不要重复的发帖,你的问题我已经在其他帖子中有回答,另外你注意仔细查看本版帖子,早就有你要的答案了

UGNX_lover · 发表于 2010-3-4 11:37:48

太好了非常好的一手资料

860604 · 发表于 2010-3-4 20:26:57

好东西哦怎么没有人做PM后处理制作视频啊

fongan3 · 发表于 2010-4-2 17:56:56

提示: 作者被禁止或删除内容自动屏蔽

hmaoming · 发表于 2010-4-3 19:55:05

感谢分享，可惜我看不懂！

johnny1217 · 发表于 2011-12-1 22:40:44

谢谢版主的分享

zwz9 · 发表于 2011-12-10 08:41:39

看了看不理解我自己做宏时是一步一步记录下来的再改变参数实现自己的要求。
楼主这一大堆我看晕了

在这里想知道单张已选面，用什么方法可以代替。做宏时用到

		自动登录	找回密码
密码			注册

通知

[公告] PowerMILL 指令收集帖

马上注册，结识高手，享用更多资源，轻松玩转三维网社区。

评分

我也参与下

fongan3 fongan3 当前离线积分 445 UID 863024 主题在线时间小时注册时间 2008-11-30 头像被屏蔽	发表于 2010-4-2 17:56:56 \| 显示全部楼层来自：中国江苏苏州提示: 作者被禁止或删除内容自动屏蔽

	回复支持反对举报